Press [EDIT]. Navigate to the VPS tab > PROBING > CALIBRATION > Tool Probe Calibration.

Load a calibration tool of known gauge length and diameter into the spindle.

Enter the calibration tool guage length and diameter into the VPS template. 

Use Handle Jog to position the calibration tool coaxial to and about .25 inch above the table probe stylus.

Navigate to the ORIENTATION variable and enter the number that corresponds to the orientation of the table probe in the machine.

Press [CYCLE START] to run the calibration cycle.

Navigate to the VPS > PROBING > CALIBRATION > Spindle Probe Length Calibration.

Enter the tool number of the spindle probe into the VPS template.

Press [CYCLE START] to run the calibration cycle.

Secure a ring gauge of know diameter to the machine table using magnets or toe clamps.

Enter the ring gauge diameter into the VPS template.

Use Handle Jog to position the spindle probe ruby in the center of and about .25 inch below the top of the ring gauge.

Press [CYCLE START] to run the calibration cycle.

If the machine generates probe alarms.  Please refer to Wireless Intuitive Probe System - WIPS - Troubleshooting Guide.

Test the Work Probe

• Start the Work Probe as follows:

Operate this code in MDI mode: M59 P2; G04 P1.; M59 P3

• The lights on the OMI will turn off and a green light will start flashing on the probe.
• If the probe operates correctly, you hear a "beep" each time you tap the probe tip.
• Stop the Work Probe as follows:

Operate this code in MDI mode: M69 P3 

• If the probe operates correctly, light on the OMI goes on, and the green light on the probe does not flash.

Install a co-axial indicator into the chuck. Install the probe into the appropriate tool holder. For instructions see the installation guide linked above.

Go to VPS by pushing [EDIT] and use the arrow keys to navigate to VPS [1] >PROBING>CALIBRATION>Step 1 (Tram and Indicate Work Probe) [2].

To select the tool position that your probe was installed in press [Tnn] and [ATC FWD] or [ATC REV]. This will call the probe into position.

Push [SETTING] and use the arrow key to navigate to User Positions>Spindle Center Line. Write down the X-position [3] stored in the appropriate setting for the type of turret on your machine. VDI/Hybrid turret: Setting 319 or BOT/BMT turret: Setting 320

Hand Jog the X-axis to the written down X-position. Make sure that the Y-axis position is zero. Then Hand Jog the Z-axis so the co-axial indicator will sweep the probe stylus tip.

Sweep the probe stylus tip with the indicator. Keep the two tapered setscrews [1] snug and adjust the four flat setscrews [2] until the probe stylus tip is inline with the spindle centerline NTE 0.0005" (0.0127mm). Make sure all of the setscrews are tight when the alignment is done.

Push [OFFSET] then use the arrow keys to navigate to Tool tab and then to the X Geometry column for the tool number that the probe is in. Push either [F2] for a VDI/Hybrid turret or [F3] for a BOT/BMT turret. This will set the X-axis Geometry Offset. 

Important : If your machine is not equipped with ATP or the work probe is incompatible with the ATP option refer to the section below.

Index the turret to the tool position that the probe is installed in. Default is the current active tool number.

Enter the Work Probe Offset that the probe will use.

Warning: Check that the probe arm has room to extend or damage may occur.

Push [F2] to extend the probe arm.

Hand jog the probe tip to within (.25”/6mm) of the ATP probe.

Push [CYCLE START] to set the Work Probe Z Geometry Offset.

To create a Gauge Ring you will need the necessary tools to face, turn an ID bore, and turn an OD diameter. Round stock is needed to create the gauge ring. Recommended dimensions are Ø3.0” and 3.0” in length.

Use the ATP to probe all the tool geometry offsets for the tools needed to machine the Gauge Ring.

Set the Work Offset used (G54-G59).

Machine the gauge ring by facing the part, bore the ID, and turn the OD. 

Write down the work offset used to machine the Gauge Ring. (G54-G59)

Once you have machined the necessary features of the Gauge Ring continue to calibrate the Work Probe to the Master Gauge Ring.

Dimension the Gauge Ring’s OD and ID using the proper measuring tools and record the values. The precision of the tool should at least be 0.0001”.

Note: Do not remove the part from the chuck to measure the part. Doing so will cause the part to not be aligned to Spindle Center Line.

Index the turret to the tool position that the probe is installed in. Default is the current active tool number.

Enter the Work Probe Offset that the probe will use.

Enter the Gauge Ring Work Offset that was written down to use as a reference point.

Enter the reference diameter which is calculated as (OD+ID)/2.

Enter the Z Rapid Approach distance from the face of the material.

Note: Recommended value is 0.5.

Push [CYCLE START] to probe the Face of the Master Gauge Ring.

Index the turret to the tool position that the probe is installed in. Default is the current active tool number.

Enter the Work Probe Offset that the probe will use.

Enter the Gauge Ring Work Offset that was written down to use as a reference point.

Enter 1 for OD Calibration and push [ENTER].

Enter the measured OD dimension that was recorded.

Enter the Z Rapid Approach distance from the face of the material.

Note: Recommended value is 0.5.

Enter the X Distance to position the probe away from the diameter to be measured.

Note: Recommended value is 0.25.

Enter the Z Distance the probe will move before probing the OD.

Note: Recommended value is 0.25.

Push [CYCLE START] to probe the OD of the Master Gauge Ring.

Enter 2 for ID Calibration and push [ENTER].

Enter the measured ID dimension that was recorded.

Enter the Z Rapid Approach distance from the face of the material.

Note: Recommended value is 0.5.

Enter the X Distance to position the probe away from the diameter to be measured.

Note: Recommended value is 0.25.

Enter the Z Distance the probe will move before probing the ID.

Note: Recommended value is 0.25.

Push [CYCLE START] to probe the ID of the Master Gauge Ring.

This procedure will show you how to make your own WIPS Calibration Tool.

A calibration tool is a tool of known length and diameter and is used for the Haas WIPS system and HTS400 presetter.

Place an end mill or a gauge pin in an ER tool holder.

The end mill or gauge pin must be straight, true, and round.

Measure the diameter using a micrometer and take note of the value.

Note: Do NOT use tool holders with set screws such as a Weldon tool holder.

Place the tool in the spindle and check the runout.

Place a tenths indicator on the table and sweep the diameter, use a small hammer to true it in the holder.

Once finished, the runout should be .0000 inch.

Use the tenth's indicator and zero the indicator on the bottom of the tool as shown in [1].

On the pendent press [POSITION] and page over top the [OPERATOR] tab and type [Z] and press [ORIGIN] to zero out the z-axis position [2].

Jog the z-axis off the indicator and position it so that the indicator is zeroed out on the spindle face as shown in [1].

Use the value shown on the operator page [2] as the tool length.

Keep and record the tool measurement values and the tool can now be used as the calibration tool.

Note: If you are recalibrating the machine using a different tool, all offsets must be re-measured.