Operate this code in MDI mode for 3 minutes:

M104; (Tool Presetter Down)

G04 P4;

M105; (Tool Presetter Up)

G04 P4;

M99;

If the ATP arm [2] does not align with home block [1], use the 3/8-24" setscrew [3] to move it toward or away from the home block.

Make sure to tighten the locknut to the adjusted position.

Operate this code in MDI mode: M104. This lowers the ATP arm.

Install a turning-stick tool into the first pocket of the turret.

Jog the X and Z axes so that the tip of a turning-stick tool [2] is near the probe stylus [1].

If the tool does not align with the center of the stylus, turn the top 3/8-24" x 2" setscrew [3] to move the stylus up or down.

Make sure to tighten the locknut to the adjusted position.

Attach the magnetic base of a dial indicator to the turret.

Move the indicator across the probe stylus.

The probe stylus must be parallel to the Z Axis. The error must be less than 0.0004" (0.01 mm).

If necessary, loosen the probe stylus screws [1] [2] and adjust the position.

 Note: There are two types of stylus used with this ATP, one with two adjustment screws [1] and another with a single adjustment screw [2].

The position of the ATP stylus is established by 4 settings: 59, 60, 333, and 334.

Measure the width of the stylus in the Z axis using a micrometer and enter that value into setting 334.

Set setting 333 to 0.0.

Press [SETTING].  Navigate to the user position tab.  Arrow down and select Spindle Cener Line.

Write down the spindle center line value that matches the tooling style used to mount the drill/mill tool.

Index the drill/mill tool to the active position.

Jog the shank of the tool close to the X+ face of the stylus.

Set the handle jog rate to .0001 resolution and hold down the X- jog key until the ATP is triggered and the machine beeps.  Jogging will automatically halt.

Write down the machine X position.

Set setting 59 = (Machine X position - Spindle Center Line) - drill/mill shank diameter

Jog the shank of the tool close to the X- face of the stylus.

Set the handle jog rate to .0001 resolution and hold down the X+ jog key until the ATP is triggered and the machine beeps.  Jogging will automatically halt.

Write down the machine X position.

Set setting 60 = (Machine X position - Spindle Center Line) + drill/mill shank diameter

Press [CURRENT COMMANDS].  Navigate to the Macro Vars tab.

Set the macro variables equal to the following settings:

• #10582 = Setting 59
• #10583 = Setting 60
• #10584 = Setting 333
• #10585 = Setting 334

Set the tool offsets of an OD turning tool using the ATP.

Generate a G-Code program to turn the OD of a piece of round stock.  Run the program and measure the resulting OD.

Subtract the programmed diameter from the measured diameter.  It should not be greater than .004.

Add the difference to Setting 59.

Update Macro variable #10582 with the new Setting 59 value.

Set the tool offsets of an ID turning tool using the ATP.

Generate a G-Code program to turn the ID of a piece of round stock.  Run the program and measure the resulting ID.

Subtract the programmed diameter from the measured diameter.  It should not be greater than .004.

Add the difference to setting 60.

Update Macro variable #10583 with the new Setting 60 value.

Push [OFFSET] until TOOL GEOMETRY [1] is selected.

Record the value in the OFFSET 1

 Caution: Be sure to accurately record this value.

Make sure that the ATP arm does not hit parts of the machine.

Push [CURRENT COMMANDS].

Select the Devices tab

Select the Mechanisms tab

Highlight Probe Arm

Push [F2] to lift the ATP arm.

Push [F2] to lower the ATP arm.

 Note: For Classic Haas Control, the button sequence is as follows:

Go into MDI mode.

Push [PROGRAM].

Select the PROBE tab [1].

Push [F1] to lift the ATP arm.

Push [F1] to lower the ATP arm.

Make sure a turning-stick tool is installed in the first pocket.

Make sure the first pocket faces the spindle.

Jog the X and Z Axes to the center of the probe stylus [2].

Make sure that you have space [1] between the probe stylus [2] and the turning-stick tool.

Push [OFFSET] one or two times to go to the TOOL GEOMETRY display.

Select the OFFSET 1 value.

Push [0]. Push [F2]. This removes the OFFSET 1 value.

If you get a warning message [1], Push [Y] to select YES.

Push [.001/1.].

Push and hold [-X] until the stick tool touches the probe.

 Note: You hear a beep sound when the stick tool touches the tool probe.

Record the value in the OFFSET 1.

Jog the X Axis away from the ATP arm.

Do steps 2, 3, and 4 four times.

Compare the highest and lowest recorded values. If the difference is more than 0.002 (0.05 mm), you must measure and adjust the 3/8-24" x 2" setscrew installed into the ATP arm.

The 3/8-24" x 2" setscrew is possible not tightened correctly. If this occurs, do the Automatic Tool Presetter (ATP) - Alignment sub-procedure.

Put the recorded values from step 1 into the OFFSET values for TOOL 1.

Use the M104 and M105 commands in MDI mode to make sure the ATP operates correctly.

M104; (Tool Presetter Down)

M105; (Tool Presetter Up)

Install an OD turning tool in the turret tool 1 station [2].

Install a workpiece in the chuck [1].

Make a cut along the diameter of the workpiece in the negative Z-axis direction.

Push [HAND JOG].

Push[.001].

Hold down [+Z] to move the tool away from the part.

Stop the spindle.

Measure the diameter of the cut made on the workpiece [3].

Push [X DIAMETER MEASURE] to put the value into the [OFFSET] column for the X-axis.

Enter the workpiece diameter.

Push [ENTER].

This adds the value to the [OFFSET] column value.

Record this value as a positive number.

This is Offset A. Change Settings 59 through 61, 333, and 334 to 0.

Move the tool away [1] to a safe position out of the ATP arm path [2].

Operate this code in MDI mode: M104. This moves the ATP arm to the down position.

Jog the Z-axis to align the tool tip [3] with the center of the stylus [4].

Jog the X-axis to move the tool tip to 0.25" (6.4 mm) above the probe stylus.

Push[.001].

Hold down [-X] until the probe makes a "beep" sound and stops the tool.

Record the X-axis [OFFSET] column value as a positive number.

This is Offset B.Subtract Offset B from Offset A.

Enter the result as a positive value into Setting 59

Measure the width of the stylus [1].

Enter this value as a positive number for Settings 63 and 334.

If the probe stylus is calibrated correctly, the values from [X DIAMETER MEASURE] and the value from the stylus are equal.

Multiply the probe stylus width by two. Subtract that value from Setting 59. Enter this value as a positive number into Setting 60. Setting 333 will remain zero.

Change the below macro values to match the setting values.

• Setting 59 = #10582
• Setting 60 = #10583
• Setting 63 = #10585
• Setting 333 = #10584
• Setting 334 = #10585

Note: The automatic probing cycles uses these macro variables to verify calibration is complete. If the values do not match the probing cycle, the machine will generate an alarm.